- 9.Configurations for draft
Much like you create a configuration for your exploded view, you can create configurations for later use in your draft views. To do this you need to first turn off all the components that you wish to exclude from the view. Then create a new configuration of the components you want to show in the draft view. To do this, select the configuration command:
Click on the New button.
Enter in the name of this new configuration.
You can later place this named configuration as a separate view onto a draft sheet.
- 10.Placing configurations in Draft
When placing an assembly into a draft sheet, using the Drawing View Wizard, you can select from a list of configurations or zones.
Only the components in that configuration will be visible in the draft view.
Note:If you wish to create a parts list of this configuration, you can set the Part List to only show the configuration components. To do this, open the properties of the Parts List and go to the List Control tab. Notice the Configuration option half way down the right side. Expand this and select the desired configuration.
- 11.Placing section views in Draft
To place an assembly section view into a draft view, you must first place the assembly into the view. You then right click on to view and go to the view properties. On the Section tab you will find a list of all the assembly section views. Simply select the desired section view and then update the views to convert the assembly view into the section view.
- 12.Drawing View Depth
By specifying a drawing view display depth for a back clipping plane, you can simplify any type of drawing view so that geometry behind the plane is removed from the view. This feature can be used, for example, to reduce the visible clutter behind a section view or a broken-out section view.
The Set Drawing View Depth command is found on the shortcut menu when you RMB click on the view.
You can type in a back clipping plane depth or use the companion view to set a depth.
You can remove the drawing view depth by using the Remove defined Depth command on the shortcut menu.
- 13.Dimension Automatic Arrangement
Use the Arrange Dimensions command to automatically group, select, and arrange linear dimensions so they don’t overlap drawing view geometry and annotations.
There are three different ways to arrange dimensions;
- I.Select a dimension
- II.Fence select – drag a fence around the dimensions
- III.Select a drawing view will select all dimensions for that view.
Note:This automatic arrangement command now makes it easy for you to use the Retrieve Dimensions command and quickly arrange the retrieved dimensions.
Thus ends our baker’s dozen tips and tricks. If all or most of these are new to you, consider upgrading your skills by attending one of our training courses. Here’s the link to the standard courses we offer; http://www.designfusion.ca//technical-training.html. We can also arrange custom training to meet your company’s needs. For more information contact your Account Rep or contact us at [email protected]