We’ve had several calls, on our tech line, asking us if Solid Edge can automatically determine the number of holes in a part, and place that value in a callout. If you are using Solid Edge ST9, and the holes were placed with the hole command, the answer is yes. To achieve this, new Feature Reference Values were added to the Symbols and Values, in Solid Edge ST9.
To illustrate how this works, I will use the following draft document as an example:
I start by selecting the Callout command, from the Annotation group.
In the Callout Properties dialog, I select the Select Symbols and Values icon.
I first expand the Values section, and then expand the Feature References section, in the Select Symbols and Values dialog.
When I scroll down, I notice that 3 new values have been added to the list.
These new values will provide the quantity count for:
%QC – all coplanar holes of the same size and type.
%QP – all parallel holes of the same size and type.
%QA – all holes of the same size and type.
Continuing with our example, I highlight the %QC and hit the Select button.
Notice that a preview is provided, at the bottom of the dialog. I then click the OK button to return to the Callout Properties dialog.
Notice that the %QC value is placed in the Callout text field.
In the Callout text field, I continue by typing a space, the letter x, and another space. I then select the Diameter symbol and the Hole Size feature reference.
Note: Remember you can save this Callout text for reuse on other Solid Edge documents.
I click OK, to dismiss the dialog, and then select the 3 holes, shown below, to place the callouts.
Notice that only coplanar counts are given. I then repeat this process using %QP, as shown below, I get the following results.
Notice that the counts on the top view are identical, because all the holes reside on parallel planes.
I then repeat this process using %QA, as shown below, I get the following results.
Notice that the counts are identical for all 3 callouts, because %QA looks for all the holes in the part, regardless of their orientation.
In the previous example, I used the Callout command. I can also place these new values in the Modify Dimension Style dialog box. For example, I could place them in the Smart Depth Tab as shown below:
Then, when I use the Feature Callout option in any of the dimension commands, I get the same results as using the Callout command.
In closing, I’d like to re-emphasize, that these values only work on “like” holes that were created by using the Hole command. They do not work on cutouts. How does Solid Edge define “like” holes? Solid Edge looks at the following settings in the holes:
If these settings are the same for two holes, then they are considered to be like holes.
If this, or any other information, in this article, is unknown to you. You may want to consider attending one of our 2-day Advanced Draft courses. For a complete course syllabus, got to http://www.designfusion.ca//technical-training.html, and scroll down to the Solid Edge Advanced Drafting course description.